ZN10StackTraceC1Ev error #214

ananddoss2004 · 2020-08-10T08:19:42Z

ananddoss2004
Aug 10, 2020

Hello Experts,

I am getting the following error while running chtMultiRegionFoam. Can anyone help me sort out this error since it is not easily understandable.

 ZN10StackTraceC1Ev [0x705c1465+0x25]
                 module: C:\PROGRA~1\BLUECF~1\ThirdParty-5.x\platforms\mingw_w64GccDPInt32\lib\libstack_trace.dll
        ZN4Foam5error10printStackERNS_7OstreamE [0x11e1c88+0x218]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZN4Foam6sigFpe13sigFpeHandlerEi [0x11e2af3+0x33]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        (No symbol) [0x40684d]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        _C_specific_handler [0x7ff853207ff8+0x98]
                 module: C:\WINDOWS\System32\msvcrt.dll
        0_chkstk [0x7ff854af00ef+0x11f]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        RtlRaiseException [0x7ff854a9b474+0x434]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        KiUserExceptionDispatcher [0x7ff854aeec1e+0x2e]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        ZN4FoamdvERKNS_5UListIdEES3_ [0x11894f5+0x75]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        (No symbol) [0x401dba]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x48de41]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x4013f7]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x40152b]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        BaseThreadInitThunk [0x7ff8543b6fd4+0x14]
                 module: C:\WINDOWS\System32\KERNEL32.DLL
        RtlUserThreadStart [0x7ff854a9cec1+0x21]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll

wyldckat · 2020-08-10T15:10:42Z

wyldckat
Aug 10, 2020
Maintainer

Greetings @ananddoss2004,

The two errors that I can see from the stacktrace are the following:

ZN4Foam6sigFpe13sigFpeHandlerEi -> sigFpe
ZN4FoamdvERKNS_5UListIdEES3 -> Foam::UList

The second one seems a bit strange, but the first one indicates a sigFpe, namely "Signal Floating Point Error": https://en.wikipedia.org/wiki/Signal_(IPC)#SIGFPE

In order to get a more accurate indication of what exactly failed, please follow the instructions given here: https://github.com/blueCFD/Core/wiki/Quick-notes-on-how-to-update-build#setting-up-the-work-environment - which will tell you how to activate the X: drive, which will allow the stack tracer to get a more accurate depiction of what went wrong.

The run the solver once again and when it crashes, provide us with the full stack trace once again, including the lines of text that come before that.

Best regards,
Bruno

0 replies

ananddoss2004 · 2020-08-10T17:19:47Z

ananddoss2004
Aug 10, 2020
Author

Greeting Bruno (wyldckat),

I followed your steps and attaching the full stack trace of the result below.

Build  : 5.x-963176928289
Exec   : C:/PROGRA~1/BLUECF~1/OpenFOAM-5.x/platforms/mingw_w64GccDPInt32Opt/bin/chtMultiRegionFoam.exe
Date   : Aug 10 2020
Time   : 22:36:47
Host   : "DESKTOP-IEFMJCU"
PID    : 6756
I/O    : uncollated
Case   : C:/Openfoam_Models/Meshing/check
nProcs : 1
SigFpe : Enabling floating point exception trapping (FOAM_SIGFPE).
fileModificationChecking : Monitoring run-time modified files using timeStampMaster (fileModificationSkew 10)
allowSystemOperations : Allowing user-supplied system call operations

// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
Create time

Create fluid mesh for region domain0 for time = 0

Create solid mesh for region insideZone for time = 0

*** Reading fluid mesh thermophysical properties for region domain0

    Adding to thermoFluid

Selecting thermodynamics package
{
    type            heRhoThermo;
    mixture         pureMixture;
    transport       const;
    thermo          hConst;
    equationOfState perfectGas;
    specie          specie;
    energy          sensibleEnthalpy;
}

    Adding to rhoFluid

    Adding to UFluid

    Adding to phiFluid

    Adding to gFluid

    Adding to hRefFluid

    Adding to ghFluid

    Adding to ghfFluid

    Adding to turbulence

Selecting turbulence model type laminar
Selecting laminar stress model Stokes
Selecting radiationModel none
    Adding to KFluid

    Adding to dpdtFluid
    Adding MRF

No MRF models present

    Adding fvOptions

No finite volume options present

*** Reading solid mesh thermophysical properties for region insideZone

    Adding to thermos

Selecting thermodynamics package
{
    type            heSolidThermo;
    mixture         pureMixture;
    transport       constIso;
    thermo          hConst;
    equationOfState rhoConst;
    specie          specie;
    energy          sensibleEnthalpy;
}

    Adding to radiations

Selecting radiationModel none
    Adding fvOptions

Creating finite volume options from "system/fvOptions"

Selecting finite volume options model type scalarSemiImplicitSource
    Source: heat_Source
    - selecting all cells
    - selected 14396 cell(s) with volume 7.635318
Generating stack trace...


Backtrace:
        0__tcf_0 [0x705c1465+0x35] (stack_trace_win.C:169)
                 module: C:\PROGRA~1\BLUECF~1\ThirdParty-5.x\platforms\mingw_w64GccDPInt32\lib\libstack_trace.dll
        printStack [0x10f1c88+0x218] (printStack.C:96)
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        sigFpeHandler [0x10f2af3+0x33] (signals\sigFpe.C:79)
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        _gnu_exception_handler [0x40684d+0xcd] (C:\repo\mingw-w64-crt-git\src\mingw-w64\mingw-w64-crt\crt\crt_handler.c:                                                                                           270)
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        _C_specific_handler [0x7ff853207ff8+0x98]
                 module: C:\WINDOWS\System32\msvcrt.dll
        0_chkstk [0x7ff854af00ef+0x11f]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        RtlRaiseException [0x7ff854a9b474+0x434]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        KiUserExceptionDispatcher [0x7ff854aeec1e+0x2e]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        operator/ [0x10994f5+0x75]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        compressibleCourantNo [0x401dba+0xaa] (fluid\compressibleCourantNo.C:41)
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        0000main [0x48de41+0x6671] (X:\OpenFOAM-5.x\src\OpenFOAM\primitives\Scalar\doubleFloat.H:107)
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        __tmainCRTStartup [0x4013f7+0x247] (C:\repo\mingw-w64-crt-git\src\mingw-w64\mingw-w64-crt\crt\crtexe.c:343)
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        mainCRTStartup [0x40152b+0x1b] (C:\repo\mingw-w64-crt-git\src\mingw-w64\mingw-w64-crt\crt\crtexe.c:221)
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        BaseThreadInitThunk [0x7ff8543b6fd4+0x14]
                 module: C:\WINDOWS\System32\KERNEL32.DLL
        RtlUserThreadStart [0x7ff854a9cec1+0x21]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll

-attached the original file below.
check.zip

Regards,
Anand

0 replies

wyldckat · 2020-08-11T12:48:54Z

wyldckat
Aug 11, 2020
Maintainer

Hi Anand,

This gives us a much clearer picture :)
The sigFPE still occurs, now indicating that it occurred due to a division gone wrong:

operator/ [0x10994f5+0x75]
compressibleCourantNo [0x401dba+0xaa] (fluid\compressibleCourantNo.C:41)

Since now we have a specific line where the issue occurs, we can go to the source code... namely line 41 goes wrong here: https://github.com/blueCFD/OpenFOAM-dev/blob/blueCFD-Core-5.x/applications/solvers/heatTransfer/chtMultiRegionFoam/fluid/compressibleCourantNo.C#L37

    scalarField sumPhi
    (
        fvc::surfaceSum(mag(phi))().primitiveField()
      / rho.primitiveField()
    );

So whatever is going on wrong, is because the rho field is zero or infinite.

Based on this information I've looked at the files in the 0 folder and the problem seems to be that you have the p_rgh field set to zero, which is prohibited in this version. Given that there is heat exchange, in OpenFOAM 5 you must use the absolute pressure values (minus the hydrostatic term for the p_rgh field), given that it will calculate the rho based on pressure and temperature, using absolute values.

Best regards,
Bruno

0 replies

ananddoss2004 · 2020-08-11T16:25:22Z

ananddoss2004
Aug 11, 2020
Author

Hi Bruno,

Although it solve sigFpe error, now i have patch field error that i am posting below.

Build  : 5.x-963176928289
Exec   : C:/PROGRA~1/BLUECF~1/OpenFOAM-5.x/platforms/mingw_w64GccDPInt32Opt/bin/chtMultiRegionFoam.exe
Date   : Aug 11 2020
Time   : 21:40:07
Host   : "DESKTOP-IEFMJCU"
PID    : 10892
I/O    : uncollated
Case   : C:/Openfoam_Models/Meshing/check
nProcs : 1
SigFpe : Enabling floating point exception trapping (FOAM_SIGFPE).
fileModificationChecking : Monitoring run-time modified files using timeStampMaster (fileModificationSkew 10)
allowSystemOperations : Allowing user-supplied system call operations

// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
Create time

Create fluid mesh for region domain0 for time = 0

Create solid mesh for region insideZone for time = 0

*** Reading fluid mesh thermophysical properties for region domain0

    Adding to thermoFluid

Selecting thermodynamics package
{
    type            heRhoThermo;
    mixture         pureMixture;
    transport       const;
    thermo          hConst;
    equationOfState perfectGas;
    specie          specie;
    energy          sensibleEnthalpy;
}

    Adding to rhoFluid

    Adding to UFluid

    Adding to phiFluid

    Adding to gFluid

    Adding to hRefFluid

    Adding to ghFluid

    Adding to ghfFluid

    Adding to turbulence

Selecting turbulence model type laminar
Selecting laminar stress model Stokes
Selecting radiationModel none
    Adding to KFluid

    Adding to dpdtFluid

    Adding MRF

No MRF models present

    Adding fvOptions

No finite volume options present

*** Reading solid mesh thermophysical properties for region insideZone

    Adding to thermos

Selecting thermodynamics package
{
    type            heSolidThermo;
    mixture         pureMixture;
    transport       constIso;
    thermo          hConst;
    equationOfState rhoConst;
    specie          specie;
    energy          sensibleEnthalpy;
}

    Adding to radiations

Selecting radiationModel none
    Adding fvOptions

Creating finite volume options from "system/fvOptions"

Selecting finite volume options model type scalarSemiImplicitSource
    Source: heat_Source
    - selecting all cells
    - selected 14396 cell(s) with volume 7.635318
Region: domain0 Courant Number mean: 0.004453225 max: 2.571433
Region: insideZone Diffusion Number mean: 0.00302761 max: 0.0232201
deltaT = 0.05813953
Region: domain0 Courant Number mean: 0.0005178169 max: 0.2990038
Region: insideZone Diffusion Number mean: 0.0003520477 max: 0.002700011
deltaT = 0.05813953
Time = 0.0581395

Pimple iteration 0

Solving for fluid region domain0
diagonal:  Solving for rho, Initial residual = 0, Final residual = 0, No Iterations 0
DILUPBiCGStab:  Solving for Ux, Initial residual = 1, Final residual = 9.501474e-009, No Iterations 1
DILUPBiCGStab:  Solving for Uy, Initial residual = 1, Final residual = 8.782644e-009, No Iterations 1
DILUPBiCGStab:  Solving for Uz, Initial residual = 1, Final residual = 2.263775e-008, No Iterations 1


--> FOAM FATAL ERROR:
cannot be called for a calculatedFvPatchField
    on patch room of field h in file "C:/Openfoam_Models/Meshing/check/0/domain0/h"
    You are probably trying to solve for a field with a default boundary condition.

    From function Foam::tmp<Foam::Field<Type> > Foam::calculatedFvPatchField<Type>::gradientInternalCoeffs() const [with                                                                                            Type = double]
    in file fields/fvPatchFields/basic/calculated/calculatedFvPatchField.C at line 187.

FOAM aborting

Generating stack trace...


Backtrace:
        ZN10StackTraceC1Ev [0x705c1465+0x25]
                 module: C:\PROGRA~1\BLUECF~1\ThirdParty-5.x\platforms\mingw_w64GccDPInt32\lib\libstack_trace.dll
        ZN4Foam5error10printStackERNS_7OstreamE [0x1211c88+0x218]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZN4Foam5error5abortEv [0xfc5b5d+0x12d]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZNK4Foam22calculatedFvPatchFieldIdE22gradientInternalCoeffsEv [0x66539740+0x100]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libfiniteVolume.dll
        ZN4Foam2fv20gaussLaplacianSchemeIddE23fvmLaplacianUncorrectedERKNS_14GeometricFieldIdNS_13fvsPatchFieldENS_11sur                                                                                           faceMeshEEES8_RKNS3_IdNS_12fvPatchFieldENS_7volMeshEEE [0x66254f3a+0x73a]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libfiniteVolume.dll
        ZN4Foam2fv20gaussLaplacianSchemeIddE12fvmLaplacianERKNS_14GeometricFieldIdNS_13fvsPatchFieldENS_11surfaceMeshEEE                                                                                           RKNS3_IdNS_12fvPatchFieldENS_7volMeshEEE [0x65f8e48f+0x8f]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libfiniteVolume.dll
        ZN4Foam2fv15laplacianSchemeIddE12fvmLaplacianERKNS_14GeometricFieldIdNS_12fvPatchFieldENS_7volMeshEEES8_ [0x661c                                                                                           8085+0x55]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libfiniteVolume.dll
        (No symbol) [0x43d59e]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x43d3c7]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x43d11d]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x48f08b]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x4013f7]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        (No symbol) [0x40152b]
                 module: C:\PROGRA~1\BLUECF~1\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\chtMultiRegionFoam.exe
        BaseThreadInitThunk [0x7ff8543b6fd4+0x14]
                 module: C:\WINDOWS\System32\KERNEL32.DLL
        RtlUserThreadStart [0x7ff854a9cec1+0x21]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll

Regards,
Anand Doss

0 replies

wyldckat · 2020-08-11T19:41:32Z

wyldckat
Aug 11, 2020
Maintainer

Hi Anand,

This actually is fairly verbal:

--> FOAM FATAL ERROR:
cannot be called for a calculatedFvPatchField
on patch room of field h in file "C:/Openfoam_Models/Meshing/check/0/domain0/h"
You are probably trying to solve for a field with a default boundary condition.

The h file in 0/domain0 cannot use the boundary condition calculated. In this specific field, it's an actual boundary that needs a condition, it cannot be merely a value calculated by the solver as a consequence of something like h=p*T.

Best regards,
Bruno

0 replies

ananddoss2004 · 2020-08-12T17:45:42Z

ananddoss2004
Aug 12, 2020
Author

Hi Bruno,

Problem solved. As you said, my temperature boundary condition is set to calculated. I changed it to fixed value and it solved the problem. Many million thanks for your support. For now, you can close the issue and I wish your support in my future endeavors.

My feedback for you: 5/5.

Regards,
Anand Doss

0 replies

Nawaraj23 · 2024-03-18T06:50:53Z

Nawaraj23
Mar 18, 2024

Hey I got the similar issue Can anyone help me with this?

$ multiphaseEulerFoam
/*---------------------------------------------------------------------------*\
| =========                 |                                                 |
| \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox           |
|  \\    /   O peration     | Version:  5.x                                   |
|   \\  /    A nd           | Web:      www.OpenFOAM.org                      |
|    \\/     M anipulation  |                                                 |
\*---------------------------------------------------------------------------*/
/*   Windows 32 and 64 bit porting by blueCAPE: http://www.bluecape.com.pt   *\
|  Based on Windows porting (2.0.x v4) by Symscape: http://www.symscape.com   |
\*---------------------------------------------------------------------------*/
Build  : 5.x-963176928289
Exec   : C:/PROGRA~1/BLUECF~2/OpenFOAM-5.x/platforms/mingw_w64GccDPInt32Opt/bin/multiphaseEulerFoam.exe
Date   : Mar 18 2024
Time   : 12:24:05
Host   : "DESKTOP-EATVDR0"
PID    : 7312
I/O    : uncollated
Case   : C:/Users/dell/Desktop/NEWFOL~1/coarse/case
nProcs : 1
SigFpe : Enabling floating point exception trapping (FOAM_SIGFPE).
fileModificationChecking : Monitoring run-time modified files using timeStampMaster (fileModificationSkew 10)
allowSystemOperations : Allowing user-supplied system call operations

// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
Create time

Create mesh for time = 0


PIMPLE: Operating solver in PISO mode

Reading field p_rgh

Calculating face flux field phi.water
Selecting diameterModel for phase water: constant
Calculating face flux field phi.air
Selecting diameterModel for phase air: constant
Selecting dragModel for phase air: blended
Selecting dragModel for phase air: SchillerNaumann
Selecting dragModel for phase water: SchillerNaumann
Selecting turbulence model type laminar
Selecting laminar stress model Stokes

Reading g

Reading hRef
Calculating field g.h

No MRF models present

GAMGPCG:  Solving for pcorr, Initial residual = 0, Final residual = 0, No Iterations 0
time step continuity errors : sum local = 0, global = 0, cumulative = 0
Courant Number mean: 0 max: 0

Starting time loop

Courant Number mean: 0 max: 0
deltaT = 0.00119048
Time = 0.00119048

PIMPLE: iteration 1
MULES: Solving for alpha.water
water volume fraction, min, max = 0.609893 0 1
MULES: Solving for alpha.air
air volume fraction, min, max = 0.390107 0 1
Phase-sum volume fraction, min, max = 1 1 1
MULES: Solving for alpha.water
water volume fraction, min, max = 0.609893 0 1
MULES: Solving for alpha.air
air volume fraction, min, max = 0.390107 0 1
Phase-sum volume fraction, min, max = 1 1 1
MULES: Solving for alpha.water
water volume fraction, min, max = 0.609893 0 1
MULES: Solving for alpha.air
air volume fraction, min, max = 0.390107 0 1
Phase-sum volume fraction, min, max = 1 1 1
Generating stack trace...


Backtrace:
        ZN10StackTraceC1Ev [0x705c1465+0x25]
                 module: C:\PROGRA~1\BLUECF~2\ThirdParty-5.x\platforms\mingw_w64GccDPInt32\lib\libstack_trace.dll
        ZN4Foam5error10printStackERNS_7OstreamE [0x11d1c88+0x218]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZN4Foam6sigFpe13sigFpeHandlerEi [0x11d2af3+0x33]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        (No symbol) [0x4047cd]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\multiphaseEulerFoam.exe
        _C_specific_handler [0x7ffe9f0bb248+0x98]
                 module: C:\WINDOWS\System32\msvcrt.dll
        0_chkstk [0x7ffea02b441f+0x12f]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        RtlFindCharInUnicodeString [0x7ffea022e466+0xa96]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        KiUserExceptionDispatcher [0x7ffea02b340e+0x2e]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll
        ZN4Foam17DICPreconditioner15calcReciprocalDERNS_5FieldIdEERKNS_9lduMatrixE [0x107b488+0xc8]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZN4Foam17DICPreconditionerC2ERKNS_9lduMatrix6solverERKNS_10dictionaryE [0x107b502+0x52]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZN4Foam9lduMatrix14preconditioner30addsymMatrixConstructorToTableINS_17DICPreconditionerEE3NewERKNS0_6solverERKNS_10dictionaryE [0x12e30af+0x2f]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZN4Foam9lduMatrix14preconditioner3NewERKNS0_6solverERKNS_10dictionaryE [0x1072447+0x117]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZNK4Foam3PCG5solveERNS_5FieldIdEERKS2_h [0x1074f3e+0x38e]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZNK4Foam10GAMGSolver18solveCoarsestLevelERNS_5FieldIdEERKS2_ [0x10896a2+0x362]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZNK4Foam10GAMGSolver6VcycleERKNS_7PtrListINS_9lduMatrix8smootherEEERNS_5FieldIdEERKS8_S9_S9_S9_S9_S9_RNS1_IS8_EESD_h [0x108a700+0x490]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZNK4Foam10GAMGSolver5solveERNS_5FieldIdEERKS2_h [0x108c92f+0x36f]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libOpenFOAM.dll
        ZN4Foam8fvMatrixIdE15solveSegregatedERKNS_10dictionaryE [0x65ef1c17+0x127]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\lib\libfiniteVolume.dll
        (No symbol) [0x4412c2]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\multiphaseEulerFoam.exe
        (No symbol) [0x473fba]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\multiphaseEulerFoam.exe
        (No symbol) [0x4013f7]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\multiphaseEulerFoam.exe
        (No symbol) [0x40152b]
                 module: C:\PROGRA~1\BLUECF~2\OpenFOAM-5.x\platforms\mingw_w64GccDPInt32Opt\bin\multiphaseEulerFoam.exe
        BaseThreadInitThunk [0x7ffe9fc9257d+0x1d]
                 module: C:\WINDOWS\System32\KERNEL32.DLL
        RtlUserThreadStart [0x7ffea026aa58+0x28]
                 module: C:\WINDOWS\SYSTEM32\ntdll.dll

1 reply

wyldckat Mar 18, 2024
Maintainer

Quick answer:

ZN4Foam6sigFpe13sigFpeHandlerEi refers to sigFpe, similar to what I mentioned in this post above: the first reply
ZN4Foam17DICPreconditioner15calcReciprocalDERNS_5FieldIdEERKNS_9lduMatrixE was the last mathematical operation that resulted in this issue... it refers to Foam::DICPreconditioner::calcReciprocal, which very likely refers to it not being able to solve the equation with the given boundary conditions.

In the first reply, you can find instructions on how to turn on the ability to see more debug details for the crash.

Alternatively, you can run one of OpenFOAM's tutorials and check what is the first equation to be solved with this solver.

Provide feedback

Saved searches

Use saved searches to filter your results more quickly

ZN10StackTraceC1Ev error #214

{{title}}

{{editor}}'s edit

{{editor}}'s edit

Replies: 7 comments 1 reply

{{title}}

{{title}}

{{editor}}'s edit

{{editor}}'s edit

{{title}}

{{title}}

{{editor}}'s edit

{{editor}}'s edit

{{title}}

{{title}}

{{title}}

{{editor}}'s edit

{{editor}}'s edit

{{title}}

Select a reply

ZN10StackTraceC1Ev error #214

ananddoss2004 Aug 10, 2020

Replies: 7 comments · 1 reply

wyldckat Aug 10, 2020 Maintainer

ananddoss2004 Aug 10, 2020 Author

wyldckat Aug 11, 2020 Maintainer

ananddoss2004 Aug 11, 2020 Author

wyldckat Aug 11, 2020 Maintainer

ananddoss2004 Aug 12, 2020 Author

Nawaraj23 Mar 18, 2024

wyldckat Mar 18, 2024 Maintainer

ananddoss2004
Aug 10, 2020

Replies: 7 comments 1 reply

wyldckat
Aug 10, 2020
Maintainer

ananddoss2004
Aug 10, 2020
Author

wyldckat
Aug 11, 2020
Maintainer

ananddoss2004
Aug 11, 2020
Author

wyldckat
Aug 11, 2020
Maintainer

ananddoss2004
Aug 12, 2020
Author

Nawaraj23
Mar 18, 2024

wyldckat Mar 18, 2024
Maintainer